Wireframe Corner Creation

Wireframe Corner Creation

Path: Insert | Wireframe | Corner

  Located in a fly-out on the Wireframe toolbar.

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Use this to ...

• Create fillets between 2D and 3D geometry.

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Prerequisites

• You should be in the Generative Shape Design workbench.

Process: Creating Corners Between Elements

1. Select Insert | Wireframe | Corner. The Corner Definition dialog displays.

2. In the Corner Type list, select an option.

3. In the Graphics window, pick the first element.

4. Pick the second element.

5. Pick the support.

6. In the Radius text box, enter a value.

7. Click Next Solution to cycle through to the required solution.

8. If required, activate Trim elements.

9. Click OK to create the corner.

Options

Corner Type

Allows you to create the corner on a support or in 3D space.

Corner On Support
Creates the corner on a support.

3D Corner
Creates the corner based on a direction you specify.

Corner On Vertex

Allows you to pick a point between 2 vertices where the corner is applied. The point is displayed in the Element 1 text box; Element 2 becomes unavailable.

Elements

Defines the geometry that CATIA creates the corner between. The elements must lie on the same plane or surface. You can create a corner from a point to a line, but the point must be the first element you pick.

Support

Defines the plane or surface that CATIA creates the corner on, if corner type is set to Corner on Support. If the elements lie on the same plane, then you do not have to specify the support plane.

Trim Elements

Trims the elements that CATIA creates the corner between.

Direction

Allows you to specify a direction that the corner radius lies along, if corner type is set to 3D Corner.

Next Solution

Cycles through possible solutions for the corner. You can also pick the solution required in the Graphics window.

Tips

• You can create geometry on-the-fly by right-clicking in the element or support boxes and selecting an option from the pop-up menu.